Estimating Injection-Molding Cooling Time Using a 1D Heat-Transfer Model

Hello. In the previous lesson, you used requirements, constraint gates, evidence confidence, and manufacturing risk to make a material choice traceable rather than intuitive. That work provides the inputs for this lesson: a candidate polymer grade, processing temperatures, and early geometry assumptions.

Now we will make the first quantitative connection between part design and molding economics. You will estimate the time needed for an injection-molded wall to cool to a safe ejection temperature using a one-dimensional heat-transfer model. The result is an early engineering estimate, not a substitute for supplier trials or mold-flow simulation, but it is accurate enough to identify whether a wall-thickness decision is likely to create an expensive cycle-time problem.

---

Cooling is a centerline problem

After molten polymer enters the cavity, heat leaves primarily through the mold surfaces. The polymer adjacent to each mold wall cools quickly; the slowest material is near the mid-plane of the wall. A part is normally limited by that hot center region, because ejecting before it has developed sufficient stiffness can cause pin push marks, distortion, warpage, or damage at thin features and undercuts.

The graph is useful for one important reason: it shows that several processes occur during a molding cycle, but they should not be confused.

• Cavity pressure rises during filling and packing, then falls after the gate freezes.
• Surface temperature responds quickly because the polymer surface is in direct contact with the tool.
• Heat flux is largest at the beginning, when the melt-to-mold temperature difference is greatest.
• Centerline temperature is not shown directly, but it generally governs the thermal estimate for ejection.

The simplified model treats a local region of the part as a flat plate of uniform thickness, cooled symmetrically from both faces by mold walls held at a constant temperature. In other words, it deliberately ignores three-dimensional effects such as ribs, bosses, gates, cooling-line layout, fiber orientation, and changing mold-wall temperature.

That simplification is useful early in design because it makes the strongest relationship visible:

$$t_c\propto s^2$$

Cooling time $t_c$ increases with the square of wall thickness $s$. A 20 percent wall-thickness increase does not produce a 20 percent cooling-time increase; it produces roughly a 44 percent increase if all other variables remain unchanged.

---

The one-dimensional cooling-time model

For an initially uniform wall cooled on both sides, a widely used one-term approximation for the time required for the wall center to reach ejection temperature is:

$$t_c=\frac{s^2}{{\pi }^2\alpha }\ln \left[\frac{8}{{\pi }^2}\left(\frac{T_m-T_w}{T_e-T_w}\right)\right]$$

where:

Symbol	Meaning	Practical interpretation
$t_c$	Cooling time	Estimated thermal time for the wall center to reach the ejection target
$s$	Full wall thickness	The complete distance between the two mold-contact surfaces, in meters
$\alpha$	Thermal diffusivity	How quickly temperature disturbances spread through the polymer, in $m^2/s$
$T_m$	Melt temperature	Actual melt temperature used for the molding process
$T_w$	Mold-wall temperature	Cavity or core surface temperature, not simply coolant supply temperature
$T_e$	Ejection temperature	Target part-center temperature at which ejection is judged safe

Two details matter immediately.

First, use the full wall thickness in this form of the equation. For a nominal $2.5\text{ mm}$ wall, use:

$$s=0.0025\text{ m}$$

Do not enter the half-thickness merely because heat moves from the center to each mold face. The equation already accounts for symmetric cooling through both faces.

Second, the temperature terms appear as differences. A temperature difference of $50^{\circ }\text{C}$ is numerically equal to $50\text{ K}$, so Celsius values are acceptable provided they are used consistently.

---

Selecting defensible inputs

The equation is easy to enter into a spreadsheet. The engineering work is selecting inputs that actually represent the part, material, and intended molding process.

Wall thickness: use the controlling local section

Begin with the thickest functionally necessary local section that cools from two accessible mold surfaces. It may not be the nominal wall shown on the drawing.

For example, an enclosure with a $2.5\text{ mm}$ nominal wall may contain:

• a $4.0\text{ mm}$ boss base;
• a rib intersection that creates a locally thick mass;
• a gasket-land transition;
• a thick solid mounting lug;
• a region near a gate that remains hotter for longer.

The one-dimensional model cannot predict these geometries accurately. Still, it gives a useful warning: if a feature creates a local mass substantially thicker than the nominal wall, its cooling behavior may dominate cycle time, sink risk, and warpage. This is one reason ribs and gussets are preferable to simply thickening a wall.

Thermal diffusivity: use grade-specific data where possible

Thermal diffusivity combines thermal conductivity, density, and heat capacity:

$$\alpha =\frac{k}{\rho c_p}$$

where $k$ is thermal conductivity, $\rho$ is density, and $c_p$ is specific heat capacity.

A material data sheet may provide $\alpha$ directly, but more often it provides only some of these properties. If you calculate it, ensure all units are compatible. A convenient conversion is:

$$1{\text{ mm}}^2/\text{s}=10^{-6}{\text{ m}}^2/\text{s}$$

Thus:

$$0.12{\text{ mm}}^2/\text{s}=1.2\times 10^{-7}{\text{ m}}^2/\text{s}$$

Thermal diffusivity changes with temperature. Filled polymers introduce additional uncertainty: glass or mineral fillers may increase conductivity, but the actual value depends on filler content, orientation, grade formulation, and processing. For early design work, record the value as an assumption, its source, and its confidence level.

Melt and mold temperatures: use process values, not generic resin-family values

$T_m$ should be the expected actual melt temperature, not merely the midpoint of a broad supplier processing range. The selected temperature affects viscosity, filling, surface quality, degradation risk, and cooling demand.

$T_w$ is the cavity or core surface temperature relevant to the part. It is not automatically equal to the coolant setpoint. Cooling-channel distance, steel conductivity, flow rate, localized heat input, and cycle balance can make the actual surface temperature different from the water temperature.

Ejection temperature: define a functional criterion

The ejection target $T_e$ should correspond to the point at which the part can be removed without unacceptable distortion or damage. Heat-deflection temperature is often a starting reference because ejection pins apply localized load to a hot, partly unsupported part. But it is not a universal ejection rule.

A robust target depends on:

• grade-specific stiffness at temperature;
• ejection-pin loading and contact area;
• wall thickness and local feature stiffness;
• use of slides, lifters, or cores;
• warpage and flatness requirements;
• handling or robotic removal loads;
• whether a visible surface is still vulnerable to marking.

---

Worked estimate: an assumed glass-filled ECU enclosure wall

Consider an early, assumption-based estimate for the base of the future high-voltage ECU housing. This does not select a production grade or represent proprietary vehicle data.

Assume the local nominal wall is $2.5\text{ mm}$, made from a preliminary PA66-GF30 candidate. The following values are placeholders that must later be replaced with supplier-grade and molding-trial data.

Input	Assumed value	Basis and limitation
Wall thickness, $s$	$2.5\text{ mm}$	Nominal enclosure wall, excluding bosses and thick mounting features
Melt temperature, $T_m$	$290^{\circ }\text{C}$	Preliminary process target only
Mold-wall temperature, $T_w$	$90^{\circ }\text{C}$	Assumed controlled mold-surface condition
Ejection target, $T_e$	$140^{\circ }\text{C}$	Initial target pending grade-specific stiffness and ejection-trial evidence
Thermal diffusivity, $\alpha$	$1.2\times 10^{-7}{\text{ m}}^2/\text{s}$	Assumed average value for a glass-filled material over the cooling range

First convert wall thickness:

$$s=2.5\text{ mm}=0.0025\text{ m}$$

Next calculate the temperature factor:

$$\frac{8}{{\pi }^2}\left(\frac{T_m-T_w}{T_e-T_w}\right)=\frac{8}{{\pi }^2}\left(\frac{290-90}{140-90}\right)$$ $$=0.8106\left(\frac{200}{50}\right)=3.242$$

The logarithmic term is:

$$\ln (3.242)=1.176$$

Now calculate the thickness-and-diffusivity term:

$$\frac{s^2}{{\pi }^2\alpha }=\frac{(0.0025{)}^2}{{\pi }^2(1.2\times 10^{-7})}=5.28\text{ s}$$

Finally:

$$t_c=5.28(1.176)$$ $$t_c\approx 6.2\text{ s}$$

The early 1D estimate is therefore approximately $6.2\text{ s}$ of thermal cooling time to the stated ejection target.

That result should be reported carefully:

For a uniform $2.5\text{ mm}$ PA66-GF30 enclosure wall, using assumed values of $T_m=290^{\circ }\text{C}$, $T_w=90^{\circ }\text{C}$, $T_e=140^{\circ }\text{C}$, and $\alpha =1.2\times 10^{-7}{\text{ m}}^2/\text{s}$, the one-dimensional centerline cooling model estimates $6.2\text{ s}$. This estimate excludes local thick features, mold cooling non-uniformity, temperature-dependent properties, fiber-orientation effects, and ejection-trial evidence.

If the program chooses an initial $20\%$ process-development allowance, the provisional planning value becomes:

$$t_{\text{plan}}=1.20(6.2)=7.4\text{ s}$$

This is a planning value, not a released production-cycle specification.

---

What thickness does to the estimate

Because the equation contains $s^2$, proportional comparison is usually more useful than recalculating every term. Holding all temperatures and thermal diffusivity constant:

Uniform wall thickness	Relative cooling time	Estimated cooling time
$2.0\text{ mm}$	$0.64$	$4.0\text{ s}$
$2.5\text{ mm}$	$1.00$	$6.2\text{ s}$
$3.0\text{ mm}$	$1.44$	$8.9\text{ s}$
$4.0\text{ mm}$	$2.56$	$15.9\text{ s}$

The difference between $2.5\text{ mm}$ and $3.0\text{ mm}$ seems small on a CAD screen, but it increases the calculated cooling time by about $44\%$. For a high-volume automotive component, that increase can affect machine capacity, unit cost, energy use, tooling decisions, and the feasibility of meeting program volume.

This is not an instruction to minimize wall thickness at all costs. A wall must still satisfy stiffness, impact, sealing, screw retention, NVH, electrical, appearance, and durability requirements. The design task is to avoid thickness that does not provide a function. Where stiffness is needed, a properly proportioned rib often produces a better structural-to-cycle-time balance than a thick solid wall.

---

Translate the estimate into a real cycle-time discussion

The calculated value is not necessarily the number entered into the molding machine’s cooling timer.

The full injection-molding cycle includes mold close, fill, pack and hold, cooling, mold open, ejection, and part handling. Some plastic cooling occurs during filling and packing. Metering the next shot may also occur while the molded part is cooling.

For a preliminary review, keep three time quantities separate:

Time quantity	Meaning	Use
$t_c$	Calculated thermal time to the stated ejection temperature	Geometry and material comparison
Machine cooling timer	The programmed period after the selected process reference point	Process setup and optimization
Total cycle time	Complete repeated molding cycle	Capacity and unit-cost calculation

A reasonable early workflow is:

1. Calculate $t_c$ for each controlling nominal wall and any suspiciously thick region.
2. Identify features whose effective thickness could make the 1D estimate non-representative.
3. Add a documented initial allowance only for planning or trial setup.
4. Confirm ejection capability using actual molded parts: dimensions, warpage, pin marking, surface condition, handling stability, and cavity-to-cavity variation.
5. Replace the planning estimate with validated cycle data and supplier simulation evidence before production release.

A short calculated cooling time is not automatically good if it is achieved by lowering mold temperature so far that surface replication, weld-line strength, residual stress, or warpage become unacceptable. Cycle time is an optimization problem constrained by quality and durability requirements.

---

Make the calculation a controlled engineering record

For each of the three component projects, create a simple Cooling Estimate Record. It is valuable because it links CAD decisions to manufacturing assumptions before supplier engagement.

Include:

Record field	Example content
Record ID	MFG-THERM-ECU-001
Part and revision	ECU base housing, concept revision
Geometry source	Onshape Part Studio/version and controlling section location
Material candidate	Exact grade if known; otherwise clearly marked family-level assumption
Inputs	$s$, $T_m$, $T_w$, $T_e$, $\alpha$, units, and sources
Model	One-dimensional plate approximation, symmetric cooling from two faces
Calculated result	$t_c$, plus any separate planning allowance
Geometry exclusions	Bosses, ribs, lug roots, gate region, insert regions, or one-sided cooling
Risks	Sink, differential cooling, ejection deformation, fiber-related warpage, insufficient cooling capacity
Verification plan	Supplier simulation, tool trial, cavity temperature evidence, dimensional inspection, ejection assessment
Maturity	Draft estimate, supplier-reviewed, trial-correlated, or superseded
Change linkage	ECO reference if wall thickness, material, mold temperature, or ejection requirement changes

In an ENOVIA environment, this record would link to the CAD part revision, material specification, manufacturing plan, CAE or mold-flow evidence, DFMEA, and change object. In the Onshape-based workflow, preserve that traceability through document versions, controlled export files, and a revision-controlled project register.

---

Key takeaways

The one-dimensional cooling model gives a fast, explainable early estimate of the time required for a molded wall center to reach an ejection target.

• Use the full wall thickness $s$, expressed in meters, and remember that cooling time varies with $s^2$.
• Define every thermal input explicitly: actual melt temperature, mold-wall temperature, ejection target, and thermal diffusivity.
• Treat thermal diffusivity, especially for filled polymers, as grade- and temperature-dependent evidence rather than a universal material-family constant.
• Use the calculation to compare geometry concepts and expose thick sections that may drive cycle time, sink, and warpage.
• Do not equate the calculated thermal time directly with the machine cooling timer or total molding cycle.
• Record assumptions, sources, limitations, risks, and validation actions so that later supplier evidence can update the design through a controlled change.

Next, you will use another core manufacturing estimate: calculating required mold clamp force from projected area, cavity pressure, cavity count, and a declared safety margin.